
What Is a UWB PCB?
A UWB PCB is a printed circuit board engineered to carry ultra-wideband signals across the 3.1–10.6 GHz band defined by the IEEE 802.15.4z standard and FCC Part 15 Subpart F. Unlike narrowband RF boards that optimize for a single frequency, a UWB PCB must maintain controlled impedance, low dispersion, and consistent radiation performance over a fractional bandwidth exceeding 100 %. This makes substrate choice, antenna topology, and transition design far more critical than on a typical 2.4 GHz board.
UWB is the backbone of centimeter-accurate indoor positioning, secure ranging for keyless entry systems, and high-resolution short-range radar. Every one of those applications transmits sub-nanosecond pulses whose fidelity depends directly on how well the PCB preserves waveform shape across the entire band.
Substrate Selection for 3.1–10.6 GHz

The substrate sets the ceiling on every other design decision. At 10.6 GHz the wavelength in FR-4 (Dk ≈ 4.4) is roughly 14 mm, so even small Dk variations cause measurable impedance shifts. Worse, FR-4’s dissipation factor (Df) rises steeply above 3 GHz, reaching 0.025 or more at 10 GHz—enough to erode link margin and distort pulse shape.
Recommended Laminates
| Laminate | Dk (10 GHz) | Df (10 GHz) | Typical Use |
|---|---|---|---|
| Rogers RO4350B | 3.48 ± 0.05 | 0.0037 | General UWB, positioning tags |
| Rogers RO3003 | 3.00 ± 0.04 | 0.0013 | Low-loss UWB radar front ends |
| Isola Astra MT77 | 3.00 ± 0.03 | 0.0017 | High-layer-count hybrid stackups |
| Panasonic Megtron 6 | 3.40 ± 0.04 | 0.0020 | Cost-sensitive UWB with digital integration |
| Standard FR-4 | 4.2–4.6 | 0.020–0.025 | Prototype only; unacceptable above ~4 GHz for most UWB |
For consumer UWB tags running NXP SR150 or Qorvo DW3000 chipsets, RO4350B offers the best cost-to-performance ratio. When the design must integrate dense digital logic (MCU, memory, power management), a hybrid stackup—RF layers in low-loss laminate bonded to FR-4 or Megtron cores for digital layers—keeps cost in check while protecting signal integrity where it matters.
Dk Flatness Matters More Than Dk Value
A UWB pulse occupies the full band simultaneously. If Dk drifts by 0.3 between 3 GHz and 10 GHz, different spectral components travel at different velocities, smearing the pulse in time—a phenomenon called group-delay dispersion. PTFE-based and hydrocarbon-ceramic laminates like the Rogers RO4350B hold Dk essentially flat across frequency, which is why they dominate UWB designs.
UWB Antenna Topologies on PCB
The antenna is often the hardest part of a UWB PCB because it must radiate efficiently from 3.1 to 10.6 GHz while fitting on a small board. Three topologies cover most designs.
Planar Monopole (Disc / Elliptical)
A copper disc or ellipse on the top layer, fed against a partial ground plane on the bottom. This is the most common UWB antenna on consumer tags. Typical size is 20 × 25 mm for a full-band design. Return loss below –10 dB across the band is achievable with careful ground-plane truncation and a tuning notch to reject the 5–6 GHz WLAN band if coexistence is needed.
Vivaldi (Tapered Slot)
An exponentially tapered slot etched into the ground plane, producing directive end-fire radiation. Gain rises from about 3 dBi at 3 GHz to 8–10 dBi at 10 GHz. Vivaldi antennas suit UWB radar and direction-finding arrays where angular resolution matters. Board area is larger—typically 40 × 50 mm—but the directivity pays for itself in link budget. More on this topology is covered in our guide to end-fire antenna design on PCB.
Printed Bow-Tie / Diamond Dipole
A balanced, planar dipole whose triangular arms create a smooth impedance taper. Bandwidth is inherently wide, but balanced feeding requires a balun or a coplanar stripline transition, adding layout complexity. Best suited to differential UWB transceivers that already provide a balanced output.
Stackup and Impedance Control
Most UWB tag designs use a four-layer stackup: signal–ground–power–signal. The top signal layer carries the antenna and RF feed; the internal ground plane is the antenna’s reference and the return path for all high-speed currents. Key rules:
- Dielectric thickness under the antenna feed: 0.2–0.3 mm (8–12 mil) of low-loss laminate for a 50 Ω microstrip width of roughly 0.4–0.5 mm on RO4350B.
- Ground plane continuity: No splits, slots, or via fences crossing under the feed line. A single slot can create a resonant notch inside the UWB band.
- Via stitching around the antenna keep-out: Place ground vias at ≤ λ/20 spacing (about 1.4 mm at 10.6 GHz) along the boundary between the antenna ground cutout and the rest of the board to suppress parallel-plate modes.
- Controlled impedance tolerance: ± 5 Ω on 50 Ω lines; specify this on the fabrication drawing with a test coupon per IPC-2141A.
For UWB positioning systems where antenna delay calibration determines ranging accuracy, the stackup must be locked down early: a 10 % change in dielectric thickness shifts the electrical delay by enough to add centimeters of ranging error.
Layout Best Practices
Feed-Line Transitions
Every transition from microstrip to the antenna element is a potential reflection point. Keep the feed line as short as physically possible—under 5 mm from the IC RF pad to the antenna feed point. If a connector (U.FL, MMCX) is needed for testing, place it on a spur with a 0 Ω resistor so it can be depopulated in production.
Component Placement and Decoupling
UWB transceivers draw fast current pulses during TX bursts. Place 100 pF and 1 nF decoupling capacitors within 0.3 mm of supply pins, and route the return current through a via directly adjacent to each cap pad back to the ground plane. Inductors in the DC-DC converter should be at least 8 mm from the antenna to avoid coupling switching harmonics into the UWB band.
Coexistence with Bluetooth LE
Many UWB modules share a board with a BLE radio for discovery and data backhaul. Separate the two antennas by at least 10 mm edge-to-edge and orient them for orthogonal polarization where possible. A ground-via fence between the two RF sections reduces coupling by 15–20 dB. For deeper guidance on BLE layout, see our article on Bluetooth LE Audio PCB coexistence.
Design Change ROI: Catching Errors Before Fabrication

A single respin of a four-layer UWB board on RO4350B can cost weeks of schedule and significant NRE. Evaluating the return on investment of catching a stackup error or antenna mismatch in simulation versus discovering it after fabrication helps justify upfront EM simulation time and prototype test-coupon runs. Enter your estimated respin cost and simulation effort below to quantify the savings.
For a typical UWB tag project, teams that run a full-wave antenna simulation (HFSS, CST, or openEMS) and a 2D impedance verification before the first board order report eliminating at least one respin cycle—often saving four to six weeks of calendar time and the cost of a second set of RF-grade panels.
UWB PCB Design Checklist
Use the interactive checklist below to verify every critical item before releasing your UWB PCB to fabrication. It covers substrate specification, impedance callouts, antenna keep-outs, via stitching rules, and coexistence spacing.
After running through the checklist, confirm that your fabrication drawing includes: the laminate part number and Dk/Df at 10 GHz, controlled-impedance line widths with tolerance, copper weight on each layer, via drill and pad sizes, and the test-coupon requirement per IPC-2141A. Missing any one of these on a UWB board almost guarantees a fabrication query that delays your order.
Testing and Validation
Once the board arrives, validate in this order:
- TDR (Time-Domain Reflectometry): Verify 50 Ω ± 5 Ω on the feed line and any transmission-line test coupons.
- VNA S11 sweep, 2–12 GHz: Confirm the antenna return loss is below –10 dB across the target UWB channels (e.g., Channel 5 at 6.5 GHz, Channel 9 at 7.9 GHz).
- Pulse fidelity test: Transmit a reference Gaussian pulse and capture the received waveform; compute the fidelity factor (correlation coefficient). A value above 0.90 is acceptable; above 0.95 is good.
- Ranging accuracy: For positioning applications, measure two-way ranging error at 1 m, 5 m, and 10 m in a controlled environment. Expect ± 5–10 cm with proper antenna delay calibration.
Frequently Asked Questions
Can I use FR-4 for a UWB PCB?
Only for low-band UWB channels (Channel 1 at 3.5 GHz, Channel 2 at 4 GHz) on very short feed lines. Above 6 GHz, FR-4’s high loss tangent and Dk variation degrade pulse fidelity and antenna efficiency to the point where link budget margins vanish. For any design spanning the full 3.1–10.6 GHz band, a low-loss laminate is necessary.
What is the minimum ground-plane size for a UWB PCB antenna?
The ground plane acts as the antenna’s counterpoise. For a planar monopole, the ground plane should extend at least 15–20 mm below the feed point and be at least as wide as the radiating element. Shrinking it further shifts the lower band edge upward and degrades omnidirectional pattern symmetry.
How many layers does a UWB PCB need?
A four-layer board (signal–ground–power–signal) is the practical minimum for a UWB tag with BLE coexistence. Simpler designs with an external antenna connector can work on two layers, but ground-return integrity suffers. Six or more layers are common when integrating a full SoC, sensors, and power management alongside the UWB radio.
Does UWB interfere with Wi-Fi?
UWB power spectral density is limited to –41.3 dBm/MHz by FCC Part 15.517, which is below the noise floor of most Wi-Fi receivers. However, the 5–6 GHz UNII bands overlap with UWB Channels 2–4. Adding a band-reject notch in the antenna or a front-end filter is standard practice when the two radios coexist on the same product.
What trace width gives 50 Ω on RO4350B for UWB?
On a 0.254 mm (10 mil) thick RO4350B core with 1 oz copper, a microstrip width of approximately 0.56 mm (22 mil) yields 50 Ω. Always verify with your fabricator’s actual copper thickness and etch compensation; a 0.05 mm width error shifts impedance by roughly 2–3 Ω at these dimensions.
Ready for a quotation?
Send your requirements for a material, stackup and manufacturing review. Price and schedule are confirmed for your project.
